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2010 Solid Edge Productivity Summit: Synchronous Assembly
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2010 Solid Edge Productivity Summit: Synchronous Assembly

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  • Demo file: … _Assembly 1 Conveyor Synch.asm
  • Demo file: … _Assembly 2 Conveyor Traditional.asm
  • Demo file: … _Assembly 3 Fork Assembly.asm
  • Demo file: … _Assembly4 Motate face.asm
  • Demo file: … _Assembly5 Releate faces.asm
  • Demo file: … _Assembly6 Transaxle small.asm
  • Demo file: … _Assembly 1 Conveyor Synch.asm
  • Demo file: … _Assembly 1 Conveyor Synch.asm
  • Demo file: … _Assembly 2 Conveyor Traditional.asm
  • Demo file: … _Assembly 8 LaserPrinter.asm
  • Demo file: … _Assembly 8 LaserPrinter.asm
  • Demo file: … _Assembly 8 LaserPrinter.asm
  • Demo file: … _Assembly7 Housing Frame.asm

2010 Solid Edge Productivity Summit: Synchronous Assembly 2010 Solid Edge Productivity Summit: Synchronous Assembly Presentation Transcript

  • 2010 PRODUCTIVITY SUMMIT ASSEMBLY
      • Synchronous Edits in Assembly
          • IPA for editing
          • Editing multiple components simultaneously
          • Live Section editing in assemblies
        • Mixed assemblies – Synchronous and Traditional parts/sub-assemblies
          • Assembly Inter-Part copies
          • Move Subassembly Components option
          • Assembly Features
      • Working with Large Assemblies
      • Custom Templates
    Assembly
  • Parts Priority (IPA)
    • Selection filter set to Parts Priority
            • Double clicking to In Place Activate
            • Full suite of part modeling tools become available
            • The PathFinder stays in the context of the assembly
    • Inter-Part Copy
            • Uses the command bar
            • Is not associative in the synchronous environment
    In Place Edit
  • Assembly Selection Filter
    • Selection Filter - Synchronous
          • Faces – Selects one or more faces for edit
            • Part must be active for face selection
          • Parts – Selects one or more parts
    • Select - Traditional
          • Many utilities for selecting parts in the assembly
    Assembly Select Tools
  • Face Priority Selection
    • Face selection filter in assembly
          • Select a single face or select multiple faces across multiple parts
          • Using the Steering Wheel you can move the faces simultaneously
            • Keypoints can be selected to move a face(s) to other geometry in the assembly
    • Selecting multiple faces on the same part will behave exactly as if you were in the part document outside the context of an assembly
          • The same Live Rules will be applied
          • Symmetry is based on the location of the base coordinate system in the part document
    Face Priority Selection
    • Selecting multiple faces on different parts will allow the faces to move together as if each part were being modified within their respective part documents
          • The same Live Rules will be applied
          • Symmetry is based on the location of the base coordinate system in each of the part documents
    Face Priority Selection
  • Assembly Motate Part/Face Together
      • Motate? It’s not a typo… Move Rotate
          • These steering wheel operations are only available in a synchronous assembly
          • If all faces of a synchronous part in a synchronous assembly are selected, the whole part is moved
          • If a traditional part or an inactive part is selected, the part will be selected and moved / rotated per the steering wheel operation
          • If individual faces of active synchronous parts are selected, live rules are displayed and drive edits
  • Assembly Motate Part/Face Together
        • Steering Wheel operations aware of assembly constraints - Part edit
          • If one or more parts are moved
            • When moving many occurrences, relationships internal to the selection are maintained
            • Relationships external to the selection are suppressed to allow the move
            • Any of these external relations that are still consistent after the move are kept, the others are deleted
            • Floating constraints are restored with new offset value
            • Fix constraint is reapplied at new location
          • If a selected part resides in a subassembly, its location in the subassembly is affected
          • If a subassembly is selected, the subassembly is affected
  • Assembly Motate Part/Face Together
      • Motate aware of assembly constraints – Face edit
          • Face edits drive assembly constraints
          • Assembly constraints do not drive faces
          • Face edits will drive assembly constraints real-time
            • Parts will move if possible during the face edit
            • When moving a face, SE always keeps the assembly relationships and the system may become over-defined because of the edit (relationship will display as “sick”)
            • Sick relationships can then be suppressed or deleted
  • Assembly Motate Part/Face Together
      • Editing Sync Part/SM Procedural features, flanges, faces
          • Faces and Edges can be stretched and rotated
            • Includes support for Relate
          • Procedural Features/SM Flanges can be stretched and rotated
            • Such as holes and patterns
          • Attribute values of Procedural features other then holes can NOT be modified from the assembly
            • IPA is required to modify Procedural Features other than holes
          • Live Rules are displayed and used to control geometry
          • Dimensions are displayed as applicable faces are selected
          • Dimensions can be used by themselves or with multiple parts/faces selected
  • Relate in Assembly
      • Using the Relate option
          • Works similarly to Relate option in Part/SheetMetal environments
          • Relations across parts are not persistent
          • Target faces can be on Synchronous or Traditional parts or sheet metal models
          • Command must be entered for each edit
          • Part must be active
  • Assembly Section Editing in Assembly
      • Section Editing is enabled within Synchronous Assemblies
          • Display of Live Sections is set under “Show Hide Components” (RMB on the part you would like to see the Live Section for)
          • Live Sections can only be created from the part level
          • Editing of parts by Live Section is only available within a synchronous assembly
          • Section edges are selectable via Quick Pick when Select is set on Face Priority
          • Edges from multiple parts can be selected with any selection set
            • Edges from multiple parts
            • Other faces or other parts
            • Dimensions can be used to drive multiple objects
  • Mixing Traditional & Synchronous Models
      • Can mix synchronous and traditional parts and assemblies
      • No restrictions on in-place activation
      • Both synchronous and traditional can be created in-place regardless of whether you are in a traditional or synchronous assembly
    Synchronous Assembly Synchronous Assembly Sync Part Trad Part Synchronous Assembly Trad Part Sync Part Trad Part Sync Part Traditional Assembly Sync Part
  • Mixing Traditional & Synchronous Models
      • Synchronous modeling available only for synchronous parts in a synchronous assembly
      • Synchronous modeling operations are NOT available for:
      • - synchronous parts in a traditional assembly
      • - traditional parts in a synchronous assembly.
    Synchronous Assembly Synchronous Assembly Trad Part Sync Part Traditional Assembly Sync Part Sync Part Trad Part
  • Mixing Traditional & Synchronous Models
      • Assembly Inter-Part:
    • Availability Determined by:
      • - Top-Level Assembly
      • - Active Document Type
    • Sync files can drive Traditional
    • Traditional cannot drive Sync
  • Mixing Traditional & Synchronous Models
      • Move Subassembly Components option
    • To move synchronous subassembly components you do not have to in-place activate them.
    • Synchronous and traditional parts in subassemblies can be manipulated from the top assembly.
    • Option is available with both Face Priority and Parts Priority
    • Traditional subassembly in a synchronous assembly is moved as a single unit
  • Mixing Traditional & Synchronous Models
      • Assembly Features:
    • Assembly Features will work on synchronous parts
    • Assembly Driven Part Features will not modify synchronous parts
    • Assembly Weldments will work with synchronous parts
    • Available in traditional assembly only
    • Click ESC during file open of an assembly and SE will stop loading the parts and just open the assembly document?
      • Dependant upon when exactly ESC is clicked during the file-open process
    Working with Large Assemblies
      • Open assembly structure not the components
      • Super fast file open allows better control of what’s opened
    Working with Large Assemblies
  • Working with Large Assemblies
    • Simplified parts in conjunction with a simplified assembly improve assembly performance
      • Faster creation of the simplified assembly representation because there are fewer total surfaces to evaluate
      • Reduced assembly document size, which reduces memory demand
  • Working with Large Assemblies
      • Display Configurations
    • Display configurations store both
      • show/hide state
      • simplified/designed state
    • Maintain Current State
      • Specifies that the current activation state (inactive or active) is not changed
      • Specifies that the current parts state (simplified/designed) is not changed
      • Setting this option improves performance of large assemblies
  • Working with Large Assemblies
      • Unloading Components
    • Unload hidden components from physical memory with the Unload Hidden Parts
      • Frees up memory for other operations
      • Makes it easier to work with assemblies with higher component counts
    • Auto-unload active parts
      • Enable via Preferences
      • Automatically inactivate parts that have not been “used” in the last “X” minutes
  • Working with Large Assemblies
      • Culling
    • Culling is active only in dynamic view manipulations
    • Instructs the display system to ignore display requests for certain objects
    • The slider ranges from 0%, where nothing is rejected, to 100%, where all objects may be rejected
    • Arc Smoothness
    • Specifies the minimum number of lines that represent an arc
    • Low values (a lower number of lines) make the display coarser
    • Consequently, low values make the display refresh faster and decrease the memory required for display lists
    • High values (a higher number of lines) make the display smoother
    • Consequently, high values make the display refresh slower and increase the memory required for display lists
    Working with Large Assemblies
    • Sharpen a View
    • Improves the display quality of the graphics
    • You can improve the display quality incrementally by:
          • Clicking the Sharpen button more than once
          • Selecting a larger number from the list
    • More accurate display will process more slowly
    • Before the highest level further Sharpen attempts produce the message "The display is at its sharpest setting."
    Working with Large Assemblies
    • For machines that have adequate supported CAD graphics cards make sure the Automatic Selection option is selected - This should set the mode to Graphics Card Driven (Advanced)
    • This setting is the optimal for the Solid Edge display system
    • If your machine does not have a graphics card that supports this option it is highly suggested that you obtain one that supports this option
    Working with Large Assemblies
    • View Transition
    • Be sure to UNCHECK this option
    • This option makes the software transition the view every time a view is manipulated from the starting orientation to the finish orientation
    Working with Large Assemblies
    • Process hidden edges
    • Be sure to UNCHECK this option
    • This option makes the software omit the hidden edge calculation during view manipulations.
    • Clearing this option can improve interactive performance during view manipulations
    Working with Large Assemblies
    • Fast locate when over PathFinder
    • Eliminates parts or sub-assemblies highlighting as the user moves the cursor across them in Assembly Pathfinder
    • Improves selection of:
        • Large sub-assemblies
        • Complex Parts
    Working with Large Assemblies
  • Working with Large Assemblies
    • Fast Locate using box display
          • Fast locate using box display for Parts:
            • Checked will display the bounding box of the part
          • Fast locate using box display for Assemblies
            • Checked will display the bounding box of all parts in the sub-assembly
  • Working with Large Assemblies
    • Occurrence properties
          • Reduce the amount of memory required when working with large assemblies
          • Higher Level - Specifies that the occurrence will be displayed when the current assembly is used in a higher level assembly
    • Drawing Views - Specifies that the occurrence will be displayed in drawing views created of the assembly in the Draft environment.
    • For specific types of assemblies, creating custom “template” Synchronous parts can offer a unique and productive method to build an assembly
    • User can set a “User Templates” path to a specific folder where these template files are stored on disk
        • Solid Edge Options
          • File Locations
            • User templates
    Using Template Shapes for Assembly Part Creation
    • As the user creates new parts in place, they can select the appropriate template file from the user templates tab
    Using Template Shapes for Assembly Part Creation
  • Using Template Shapes for Assembly Part Creation
    • If the template file’s origin is known, it can be used as the insertion point by using the “by graphic input” option
    • There is no need to Create and Edit the part
  •